our digital manufacturing ecosystem
Global Manufacturing Network
People on the ground
3D Printing Materials
Urethane Casting Materials
Digital Manufacturing Resources
Learn about fictiv
DFM for CNC Machining
2020 State of Manufacturing Report
Introducing Fictiv Radical Transparency: An Industry-First Solution for Production Visibility
Master Class contents
Manufacturing Design: Minimizing Cost & Lead Time
Design Requirements for CNC Manufacturability
Optimizing DFM for Complex Mechanical Designs
Key CNC Machining Terminology
This module introduces the “effort” model for understanding the factors that drive CNC machining cost, lead time, and risk. It shows how design parameters map to manufacturing effort and the corresponding rule set for designs that are cheapest and fastest to produce
YOU WILL LEARN
Design for manufacturability (DFM) starts with the basic test of whether a design is manufacturable or not. These rule sets, as represented in the Fictiv CNC Machining design guide, provide essential guardrails to the manufacturing design process which prevent catastrophic problems.
However, passing manufacturability checks does not mean that the design will be successful. Making the wrong decisions can lead to reachability issues, extra setups, surface defects, or other machining challenges, which translate into higher manufacturing costs and longer lead times. Many of these problems are avoidable through appropriate choice of design specification. The key to understanding the effect of different design choices is to understand how different designs require different levels of effort to manufacture.
Manufacturing Effort: A measure of time, care, and challenge to manufacture a design.
Designing for the least amount of manufacturing effort is the next level goal of DFM. Least effort scales with the complexity of the design requirements. So, for example, a design for controlling fluid flow will have a higher effort than a design of a simple test fixture. The key is to design so there is no unnecessary effort in the manufacturing process.
Least effort design is especially important if the design will be taken to production. In production, every instance of unnecessary effort translates into lower margins, lower production volume, and in the worst case can render production uneconomic. Therefore least effort manufacturing principles should be incorporated into the design process from Day 1.
There are five design parameters that determine manufacturing effort for CNC machining.
It is possible to map each design parameter to its corresponding level of effort. In some cases, multiple regions of the same parameter map to the same effort region. For example, both very small parts and very large parts map to the max effort region.
The manufacturable zone can be broken down into three regions.
High effort designs map to the extreme edges of the manufacturable region, while low effort designs map to the center. This heuristic reveals where the risk is in the design and where effort could potentially be reduced.
The least effort region for CNC machining is the region of lowest cost and fastest lead time. Any machine shop should be able to manufacture least effort designs. By pushing as many design parameters into this region as possible, designers can increase speed, lower cost, and reduce risk. In general, designs that are least effort are simpler and have no special requirements. Common low-effort parts include fixtures and brackets. Below is a description of the least effort region for each parameter.
For tolerance, the easiest option is to leave the tolerances set by the stock material. For features that are machined, ISO 2768, medium is a good balance of what is easily achievable with standard CNC machines and what is necessary for normal functional parts.
Least effort part geometry uses a stock geometry and makes the least amount of adjustment to it. Stock material comes in bars, sheets, rods, and tubes as well as other specialized shapes. Stock materials can also make certain geometries low effort–for example, using a tube and leaving the inner diameter as stock allows for an arbitrary hole depth greater than the normal 10x tool diameter guideline. If stock material is not used then gun drilling is required, which adds effort.
To machine a surface geometry, it must be reachable by the tool. This means that there is an orientation of the CNC machine and tool where the normal vector of the cutting surface is parallel to the normal vector of the part surface. Below is an example of reachability for a square end mill (shown in 2D for simplicity).
For least effort, limit geometries to what can be reached by a 3-axis machine with no 3D machining. Least effort designs are characterized by orthogonal surfaces that intersect at 90°.
Different tool geometries have different surface normals that make different surface profiles reachable. For least effort, tool geometries should be limited to:
If a part geometry is fully reachable, it will still require more than one setup to machine every surface. Least effort geometries should require no more than two setups. Parts should also have two parallel surfaces perpendicular to each machinable side, so that standard fixturing is possible.
Another very important consideration when manufacturing to a specific tolerance is the stiffness of the part during machining. Forces on the part from the tool and the fixture can cause deformation and chatter. To compensate for these issues, machinists must take extra care during fixturing and run machines slower to reduce cut forces. To reduce effort, use parts with symmetric geometries that distribute loads evenly and keep wall thickness above 3/8in [9.5mm].
Warping is another risk if there are thin walls in the geometry. The internal removed material ratio (IRMR) and external removed material ratio (ERMR) can show if this may be an issue or not. The higher these ratios are, the more likely that deformation or warping will occur. Keeping the ERMR < 80% and the IRMR < 30% can help prevent these issues.
Fixturing is one of the major contributors to manufacturing effort. Keeping part size between (0.25 in x 2 in x 2 in) and (6 in x 6 in x 6 in) means that the part should fit in the standard fixture machine shops have available. Manufacturers will have different standard sizes so it is always useful to check what the manufacturer has readily available. At Fictiv, parts are always matched to the closest stock size. Stock usually comes over sized in one dimension and then is cut down with a bandsaw. Below are standard size that are generally available:
The least effort is defined by how easy the material is to machine. Machinability is made up of multiple parameters, but the major drivers are thermal conductivity, hardness, and chip formation. The list of least effort materials is shown below and is organized by the material strength.
An easily achievable default roughness is 63μin Ra or 1.6μm Ra and higher. At Fictiv, this is the standard, unless otherwise specified.
Fillets are easy to add into CAD, but they just as easily increase manufacturing effort. The key is to know what fillets you need and what you do not. By default, the edges parallel to the tool will be filleted for a given setup and edges between compound surfaces. These are intrinsic fillets and are unavoidable. Fillet radius is set by the finish tool diameter. To minimize effort, size finish tools for greatest efficiency, and then set the fillet radius to match that diameter. For all other edges, add a note to your drawing to “break all edges”. This instruction gives the manufacturer the freedom to round those edges in the simplest way possible.
Each design decision you make ultimately results in a machinist programming a tool path, determining feeds and speeds, loading material into a fixture, and creating the part. Though each of these tasks may be small, the effort required can add up to high costs and long lead times that can put projects at risk. Understanding how to avoid unnecessary effort is especially important for designs in the Least Effort region of the manufacturable zone. See the list below for the rules for keeping designs within this region.
Download the checklist PDF as a handy reference guide here!
Least Effort Tolerance
Least Effort Geometry
Least Effort Part Size
Least Effort Material
Least Effort Look and Feel
In this webinar, we introduce you to the concept of design for least effort CNC machining. This concept will take you beyond the fundamentals of DFM (design for manufacturability), which is about do’s and don’t, and help you uplevel your DFM skills to design parts that are cheaper, faster, and less risky to manufacture. You’ll […]
In this webinar, we explore how to optimize higher complexity designs for manufacturability, where effort cannot be completely minimized. We will also explore the sources of manufacturing effort and key techniques for reducing relative effort for parts that are faster, more economic, and less risky to produce. You’ll walk away knowing: How effort scales for […]
In this webinar, we explore how to reduce manufacturing effort in the most complex designs applicable to industries such as medical devices, robotics, and aerospace. Here we will specify key risk mitigation strategies for high precision, high geometric complexity, and extreme part sizes (large and small). You’ll walk away knowing: Costs and benefit trade-offs at […]